You are not logged in.
Pages: 1
We Have a DMF180 5Axis machine B Axis in the head and A Axis as a Head/Tailstock assembly along X axis .Control is a Heidenhain iTNC530.With the A configuration "Plane Spatial" would not work but "Plane Axial " would (PLANE AXIAL A0.000 B0.000 TURN FMAX SEQ+ TABLE ROT) . I have built up Vericut machine which works Ok but control does not understand "Plane Axial" Command . Has anyone on this forum come across this situation and would you have a solution for it , Thanks in advance
Offline
I haven't come across this yet, but perhaps someone else reading this may have? I take it that you meant that PLANE SPATIAL would work but that AXIAL woud not, as it was not a recognized word.
I was looking in:
User's Manual Heidenhain Conversationl Programming iTNC 530
NC Software
340 490-xx
340 491-xx
340 492-xx
340 493-xx
340 494-xx
English (en)
8/2005
...and didn't come across a PLANE AXIAL command. Do you have any example and supporting documentation to configure this from? I did find this:
http://content.heidenhain.de/presentati ... etail.html
Which seems to indicate that PLANE AXIAL is just a simpler version of PLANE SPATIAL. I would:
Add word "AXIAL" to word format
Add a conditional to the A and B words to get the same behavior as used in SPA and SPB from PLANE SPATIAL, adjusting the text X and Y overrides based on your machine configuration:
A *
(AXIAL *) and (RELATIVE *)
RotationPlaneincAngle1
Text = X
(AXIAL *)
RotationPlaneAngle1
Text = XAdd a conditional to the word PLANE like so:
PLANE *
(AXIAL *)
WorkingPlane2Abc
Value = 0
Text = 120 121 122
Variable: CGT_ADJ_PLANE_FLAG
Value = 1That being finished you should get what you are looking for. If you run into trouble and you need immediate assistance please give Tech Support a call or email.
Offline
Thank you I will try this
Offline
Pages: 1