VERICUT Users' Forum

DS

Member

From: TULSA OK

Registered: 2006-10-25

Posts: 6

word format

Hi all,

I am getting the control def set up for a Haas lathe. The control uses a G112/G113 for xy to xc conversion. I have the word address set up so it reads the code properly.

The problem I have is the multiplier on the x axis in the word format is .5 for Diameter programming. when in G112 Vericut cuts everything half size.

How do I set a condition in the word format to correct the x multiplier when G112 is active?

Thanks in advance

Doug

danr

Member

From: Derby, UK

Registered: 2006-07-24

Posts: 19

Re: word format

Doug,

Assuming I understand you correctly and the machine uses diameter programming except when in G112 mode, I set up our controls as follows:

-Remove the multiplier from the X in the Word Format table, instead find the X word address and add an Overide Text of $/2 to the XAxisMotion macro, this takes the input value and divides by two, giving the Diameter programming in normal conditions

-In the G112 word address set a variable e.g DIAMETER to equal 1

-In the X word address set a condition to say 'When DIAMETER is equal to 1' and use the XAxis Motion macro with no Overide text, this will give the full X value when in G112 mode.

You will need to reset the variable DIAMETER when the G112 mode is cancelled to return to diameter programming.

Hope this helps.

Daniel

---

Current version: Vericut 7.0.3