VERICUT Users' Forum

pblythe

Member

From: New Zealand

Registered: 2005-04-06

Posts: 10

Website

PCD Drilling MACRO Call

Hi
Help Please.  Can you please advise how I would instruct VERICUT to call the following lines of code? Its a FANUC 15M control

T49(9.3 MM DRILL)
G90G55G00X0.0Y0.0S2000M03
G43H41Z3.0M12
G81G98R-57.0Z-65.0L0F200
G300A22.5B45.0D240.0K8.0
G80M09

The G300 is what I want to get working.  Its a PCD call to Sub Program 9011.  System Parameter 7051 is set to call Sub Program 9011 on the event of G300 being called.  The Variables A B D and K are passed to the sub programme as variables #1 #2 #4 #6 respectivly. A being the start angle of the first hole, B being the angle between each hole, D being the PCD and K being the number of holes on the PCD.
Below is the Macro Code of Program 9011
O9011(PCD MACRO)
#170=0.
#173=#6
#174=#7/2.
#175=#4014
#176=#4001
#177=#4003
#173=#173-1.
WHILE[#173GE#170]DO1
#178=#170*#2
#171=COS[#1+#178]*#174
#172=SIN[#1+#178]*#174
G90X[#24+#171]Y[#25+#172]
#170=#170+1.
END1
G#175G#176G#177
M99

Many thanks in advance

Peter Blythe
CNC Programmer / Coordinator
C.W.F Hamilton & Co Ltd.
P.O. Box 709
Lunns Rd, CHRISTCHURCH, NZ.

Tel: 0064 (03) 962 0504 Direct Dial

GavinP

VERICUT Specialist

From: UK

Registered: 2004-10-14

Posts: 58

Website

Re: PCD Drilling MACRO Call

Hi Pete

Have you got any subroutines in use currently ?

The actual 9011 subroutine you list needs to be included if you have, if you have no subroutines add it via Setup, Control, Adv. Options, Subroutines (tab), browse and add the file.

Control subroutines are executed without appearing in Setup, Toolpath or Info, Status as is common for many machine control resident files.

(for ease of Vericut file management many subroutines can be included in a single file)

If you wish to single block through the subroutine as a toolpath then add it via Setup, G-Code, Settings, Subroutines. You can add in both locations if needed but G-Code will be used over control.

To get Vericut to jump into and execute the subroutine do this >

Setup, Control, Adv. Options, Substitute,
Input G300
Output G65P9011
OK

Reset and test.

pblythe

Member

From: New Zealand

Registered: 2005-04-06

Posts: 10

Website

Re: PCD Drilling MACRO Call

Hi Gavin
Many thanks.. it works a treat.  I like the Tracking Variables register under SETUP - GCODE - VARIABLES. 

Many thanks for your help, I'am in the UK for three weeks at the end of August, If I bump into you, I'll buy you a pint.!

Regards
Pete